Footprint: 3.3 mm thermal land and IPC pads; TI RHB0032M land is a 2.1 mm EP with 0.6 x 0.25 pads
Footprint: the page uses a generic QFN-32 with a 3.3 mm thermal land; the RHB0032M thermal pad is 2.1 mm
The page's footprint is KiCad's QFN-32-1EP_5x5mm_P0.5mm_EP3.3x3.3mm (IPC pads 0.875 x 0.25 at +-2.4375, a 3.3 x 3.3 thermal land with nine 0.89 mm paste windows).
TI's own drawing for this part (ADS124S08 data sheet SBAS660B, RHB0032M):
- Package outline, p. 110: exposed thermal pad 2.1 +-0.1 mm square; body 4.9-5.1 mm; 1 mm max height.
- Example board layout, p. 111: 32 pads 0.6 x 0.25 mm at a 4.8 mm span, 0.5 mm pitch, R0.05; thermal land 2.1 mm square; five optional 0.2 mm vias (centre and +-0.8 mm).
- Example stencil, p. 112: four 0.94 mm square windows at +-0.57 mm (80 % of the pad, 0.125 mm stencil).
Why it matters: about 1.6 times the paste area the 2.1 mm pad can take, and the land edge sits about 0.4 mm from the inner lead ends, so the part can float or tilt and bridge on reflow.
Suggested fix: TI's RHB0032M land as above (pads 0.6 x 0.25 at +-2.4, 2.1 mm EP, the four 0.94 mm paste windows, optional 0.2 mm vias). Found with adom-aiflow part-check (adom-aiflow 0.2.93), 2026-11-20. The pin type issue on REFCOM is filed separately.
0 Replies
Log in to reply.